Create a Groove Finish Turning Operation

task target This task shows how to insert a Groove Finish Turning operation in the program. To create the operation you must define:
pre-requisites Open the Lathe01.CATPart document, then select Machining > Lathe Machining from the Start menu. Make the Manufacturing Program current in the specification tree.  
scenario 1. Select the Lathe Groove Finish Turning icon .

A Groove Finish Turning entity along with a default tool is added to the program.

The Groove Finish Turning dialog box appears directly at the Geometry tab page . 
This tab page includes a sensitive icon to help you specify the geometry to be machined.

The part in the icon is colored red indicating that this geometry is required. 
2. Click the red part in the icon then select the desired part profile in the 3D window.
In addition to the global offsets that you can assign to the selected profile, you can also add local values. 

Right-click the geometry to be assigned the local value, and select the Add Local Information contextual command. A dialog box appears allowing you to assign the desired local values.

Other contextual commands are available for analyzing and resetting local information.  Please refer to Local Information for more details.
3. Select the Strategy tab page   

to specify the main machining strategy parameters:

  • Orientation: External
  • Machining direction: To head stock
  • Contouring for outside corners: Circular.

Other optional parameters can be set in the Machining and Corner Processing tabs.
A tool is proposed by default when you want to create a machining operation. If the proposed tool is not suitable, just select the Tool tab page to specify the tool you want to use. This is described in Edit the Tool of a Lathe Operation.
4. Select the Feeds and Speeds tab page to specify the feedrates and spindle speeds for the operation. See Feeds and Speeds for Finish Grooving for more information.
In addition to the global feedrates that you can assign for the operation, you can also add local feedrates to portions of the profile. 

Right-click the geometry to be assigned the local value, and select the Add Local Information contextual command. A dialog box appears allowing you to assign the desired local values.

Other contextual commands are available for analyzing and resetting local information. Please refer to Local Information for more details.
5. Select the Macros tab page to specify the operation's transition paths (approach and retract motion, for example). See Define Macros on a Lathe Operation for an example. 
Before accepting the operation, you should check its validity by replaying the tool path.
6. Click OK to create the operation.

end of task