Sequential Axial Machining

	This task shows how to insert a Sequential Axial operation in the program. To create the operation you must define: the geometry of the holes to machine to be machined a sequence of elementary tool motions and machining strategy parameters the tool that will be used the feedrates and spindle speeds the macros (transition paths) . Please refer to Sequential Axial and Sequential Groove Operations in the Reference section for detailed information about this operation.
	Open the Sequential_Axial.CATPart document, then select `Machining > Prismatic Machining`from the Start menu. Make the Manufacturing Program current in the specification tree.
	1.	Select `Sequential Axial` . A Sequential Axial entity along with a default tool is added to the program. The Sequential Axial dialog box appears directly at the Geometry tab page .
		The `Global` tab allows you to define the hole geometry to machine.
	2.	Select the red hole depth representation in the sensitive icon, then select the three holes in the part. Just double click to end your selections. The `Global` tab is updated as shown below.
	3.	Select the `Local` tab to define the machining planes to reach. Select the plane representations in the sensitive icon, and the desired planes in the part. The `Local` tab is updated as shown below.
	4.	Select the Strategy tab page , which comprises two tabs `Motions` and `Strategy`. The `Motions` tab allows you to define the elementary motions making up the machining operation.
	5.	Click `Spindle Speed` , then define a counterclockwise spindle motion and a 60tr/mn local spindle speed. Click OK to add the first tool motion in the list in the Sequential Axial dialog box.
	6.	Click `Go to Plane` , the define a Goto a plane motion to Plane 1 and a local feedrate of 50mm/mn. Click OK to add the second tool motion in the list.

	7.	Insert other motions as follows: PP Instruction: COOLNT/CENTER,70 Delay motion: dwell time of 3sec Go to plane motion to Plane 3 at machining feedrate Go to Clearance motion with local feedrate of 500mm/mn.

	8.	Select the `Strategy` tab to specify machining parameters such as `Approach clearance`.
	9.	If needed, select the Tool tab page to replace the default tool by a more suitable one. See Edit the Tool of an Operation for more information about selecting tools.
	10.	If needed, select the Feeds and Speeds tab page to specify the feedrates and spindle speeds for the operation.
	11.	If you want to specify approach and retract motion for the operation, select the Macros tab page to specify the desired transition paths. The general procedure for this is described in Define Macros of an Operation.
	12.	Check the validity of the operation by replaying the tool path.
	13.	Click OK to create the operation.

Create a Sequential Axial Machining Operation