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This task shows you how to convert the
specifications of an
AUXVIEW2 View into a Generative Drafting View.
It is possible to copy/paste AS RESULT V4 Drafting
entities into CATIA V5, but this functionality allows you to copy/paste
AS SPEC an AUXVIEW2 View into CATIA V5. As a consequence, you can get a V5
Generative Drafting View. |
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AUXVIEW2 Defaults:
In AUXVIEW2 DEFAULT, a number of dress-up parameters on specific elements
(clipping edges, cut edges, breakout limit) are pre-defined. Refer to
Managing AUXVIEW2 Defaults for Migration for
information on what you need to do before migrating AUXVIEW2 views
from V4 to V5 to ensure that your migration results will be equivalent to
your AUXVIEW2 defaults. |
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3D Reference Document:
V4 AUXVIEW2 Views reference 3D models. V5 Generative Drafting Views also
reference a CATPart or a CATProduct. Therefore, prior to migrating AUXVIEW2
Views, you need to convert 3D models into CATIA V5 parts or products to have
this reference available. When the V4 Drawing is referencing several 3D
models, you need to migrate all the models into CATParts and create a
CATProduct referencing these CATParts. |
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During the V4 To V5 Migration (AS SPEC), different types of
views are taken into account:
- AUXVIEW2
Views are converted into Generative Drafting Views.
- AUXVIEW
Views converted into Interactive Drafting Views. The behavior is
the same when you copy/paste (AS RESULT) these entities. Transparent Views
are converted into Interactive Drafting Views.
Moreover, non-generative geometry will be migrated AS RESULT. That is to
say, an AUXVIEW2 View containing interactive entities such as a line, a
circle,... will be converted into a line, a circle.
And, dimensions and texts will be also migrated AS RESULT in the same way
you can copy/paste (AS RESULT) these elements in CATIA V5. |
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For more information about the 3D Migration, please
refer to Copying 3D from CATIA Version 4 to CATIA
Version 5. |
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Open the AUXVIEW2.model
document and the AUXVIEW2.CATPart
document. The latter will serve as the 3D reference document for the V5
Drawing.
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In the AUXVIEW2.model document, click the *DRAFT tab
(projection view):
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Click the New
icon and select Drawing from the New dialog box, to open a .CATDrawing
document.
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In the New Drawing dialog box, click OK.
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In the AUXVIEW2.model document, right-click *DRAFT in the
specification tree, and select Copy from the contextual menu.
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Activate the Drawing document, and select the Edit->
Paste Special command. The Paste Special dialog box is
displayed. Choose the paste CATIA_SPEC option.
Right after you select CATIA_SPEC, a dialog box is
displayed in which you can define the 3D Reference necessary for the V5
Drawing.
This dialog box contains two sections:
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a list of all the CATParts (for instance,
AUXVIEW2.CATPart) and CATProducts
currently open in the CATIA V5 session.
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a Browse button giving access to a File/Open dialog
box to let you specify a 3D reference other than the currently open
CATParts or CATProducts.
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Select the AUXVIEW2.CATPart document and click OK.
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Click OK in the Paste Special dialog box. The Views are
generated in the CATDrawing:
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Associativity:
Only SPECIFICATIONS of the Views are migrated; therefore, the profiles of
Section Views and Detail Views are not associative to 3D. |
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Details about V4 Drafting Entity conversion:
The following V4 View Parameters are migrated AS SPEC: |
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DRAW Elements |
V4 to V5 Migration AS SPEC |
Views
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AUXVIEW2 View |
Generative Drafting View |
AUXVIEW View |
Interactive Drafting View |
View Types |
Projection |
Projection |
Section Cut / Section View |
Section Cut / Section View |
Detail View |
Detail View |
Auxiliary
View |
Auxiliary
View |
Specific
Behavior of the View |
Simple Breakout |
Simple Breakout |
Backclipping |
Breakout |
View
Parameters |
Hidden Lines |
Hidden Lines |
Generation of Axis |
Generation of Axis |
Fillets |
Fillets |
Same/Standard |
3D Color Inheritance |
View Name Representation |
View Name Representation |
Callout Representation |
Callout Representation
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The following specifications are not yet migrated AS SPEC:
- Specific Behavior of the Views
- Unspec Breakout
- Filter on Views: UnCut/UnUse/UnHlr
- Filter on Layer, Box, View
- View Parameters:
- Representation Types of Hidden Lines
- Pattern Representation
- Lock of the generated geometry
- Old generated elements: Scratch/choose Layer
- Autolayering
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However, you can migrate the following specifications using
the migration batch (for more information, refer to
Converting V4 AUXVIEW2 Views to V5 Generative
Drafting Views in Batch Mode):
- Specific Behavior of the Views
- Filter on Views: UnCut/UnUse/UnHlr
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Migration
report:
The migration of V4 drawing
data to a V5 document generates a report (.rpt) file named after the model
migrated:
- on Windows:
in C:Documents and Settings/username/Local Settings/Application Data/DassaultSystemes/CATReport
- on UNIX: in /u/users/username/CATReport
This reports contains different types of information regarding the
migration results:
- location and name of the input and output files,
- kind of migration performed (e.g. V4 to V5 CATDrawing),
- migration mode performed (AS SPEC or AS RESULT),
- status of migration for each V4 element:
- Correctly/OK: migration successful
- KO: migration failed
- NOT: migration could not be performed for lack of a CATIA V5 equivalent.
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