Creating a Swept Flange

	This task explains how to generate a swept flange from a spine and a user-defined profile.
	The SweptWall01.CATPart document is still open from the previous task. If not, open the SweptWall04.CATPart document from the samples directory. As a profile is already defined on the part, you will be able to skip step 1 of the scenario.
	If you are using the SweptWall01.CATPart document, click the Sketcher icon , and define a profile in the yz plane as shown below:

	Then quit the Sketcher, using the `Exit` icon . If you are using the SweptWall04.CATPart, go directly to step 2 as the profile is already defined.
	Select the `Swept Flange` icon in the `Swept Walls` sub-toolbar.

	The `User Defined Flange` Definition dialog box opens.
	Select the edge and the profile, as shown in red.

	The dialog box looks like this:
	Click the `More` button to display the `Bend Allowance` tab allowing you to locally redefine the bend allowance settings. You may need to deactivate the formula using the contextual menu on the field and choosing `Formula -> Deactivate` before editing the value.

	In this case, the new K Factor value overrides the value set in the Sheet Metal Parameters.
	Click `OK` to create the swept flange.

	The feature is added in the specification tree.
	Use the `Tangency Propagation` button to select all tangentially contiguous edges forming the spine (see Selecting the Spine). You can redefine the hem limits by choosing the `Relimited` option (see Redefining Swept Walls Limits).