Creating a Projection View

1. Click New View in Layout toolbar.
   The preview of the 2D view frame along with blue knob manipulator is displayed in the sheet. Depending on a possible selection, the manipulator allows either to change the primary view type (no selection), or to change the view box orientation. If a reference element is selected, the view box size is computed based on the 3D model size, such that the view box contains the entire 3D model.
   Note that you can redefine the projection plane using the blue arrows at any time before the view creation: to the bottom, the left, the right, the top, or rotated using the given snapping or according to an edited rotation angle. For more information, refer to Defining the view orientation during view creation.
   You can change the view position by dragging the dotted green frame or press Crtl key and move the cursor to the desired location.

   When no reference plane or surface is selected from 3D, then the view box dimensions are computed from the standards (Tools > Standard > Standard_Name > Layout Views Customization). For more information, refer to Layout Views Customization.

2. Click on the sheet to position the new view.

   Note how the view is previewed in the part window. You need to zoom out, as the view box defined in the ISO_3D standard used by the current layout has sides of 1000mm. For more information on the standards, see Administration Tasks.

   An empty primary view is created, displaying a blue axis in a red frame, as well as the view name and scale. Additionally, the Front View item is added to the specification tree.

   In our scenario, the primary view is a front view. The view type for the primary view is defined in the current standard (ISO_3D in our scenario).

   You can now create 2D geometry in your view or continue creating more projection views as detailed below.

3. Click New View again and click in the layout at the location where you want the projection view to be positioned: you can create Left, Right, Top, Bottom and Isometric views. Create a Left view, for example.

   Projection views are always created from the active (current) view. Positioning the view defines the projection view direction, in accordance with the projection method and the primary view type (a front view in our scenario). The projection method (First angle standard or Third angle standard) is defined by the sheet style, as specified in the standard used by the layout. For more information, refer to Sheet Styles in the Administration Tasks chapter. You can change the projection method by editing the layout sheet properties (through Edit > Properties). Remember that it is not possible to create several projection views of a same type within a set of views (two Right views, for example). Projection views are always created using the sheet scale. The primary view scale, when it is different from the sheet scale, is not propagated to other projection views. If you change the sheet scale (defined in the sheet properties), the scale of all existing views (defined in the view properties) is multiplied by that of the sheet (for example, if existing views already have a scale of 1/10, and if you change the sheet scale to 1/10, then existing views will now have a scale of 1/100).

   The view is created. The specification tree is updated again to show the newly created view.

4. Double-click the New View icon to create several projection views one after the other: this time, create Right, Top, Bottom and Isometric views. The specification tree is updated again.

5. Press Escape when you have created your views.

6. Activate one of the projection views by double-clicking it. For example, activate the Left view.

7. Click New View again: this time, you can create Rear or Isometric views from the left view. Create a rear view, for example. The specification tree is updated again.

Defining the view orientation during view creation

1. Click the right or left arrow to visualize the left or right side, respectively.

2. Click the top arrow to visualize the bottom side.

3. Click the counterclockwise arrow to rotate the reference plane.

4. Drag the green knob to redefine the rotating angle. The default increment value is 30 degrees.

5. You can modify the increment value using the contextual menu which is available for the green knob. To do this, right-click the knob and select the desired option:

   • Free hand rotation: Lets you rotate the knob in a free manner using the mouse, instead of snapping it to a given increment.

   • Incremental hand rotation: Snaps the rotation to a given increment (from 30 to 30 degrees, between zero and 330). This is the default value.

   • Set increment...: Displays the Increment Setting dialog box. Enter the required value in the Increment value field. For example, type 5 deg (for 5 degrees) and click OK.

   • Set current angle to:

     • 0 deg: Sets the current angle value to 0 degree.

     • 90 deg: Sets the current angle value to 90 degrees.

     • 180 deg: Sets the current angle value to 180 degrees.

     • 270 deg: Sets the current angle value to 270 degrees.

     • Set angle value...: Displays the Angle Setting dialog box. Enter the required value in the current angle (deg)  field.

6. Click on the center of the knob to fix the position of the view.

7. The view is created.

• The creation of isometric views cannot be customized using the blue knob manipulator.

• It is not possible to edit the view box from an existing primary view.

• When you select a reference plane to define a primary view, the view lies on a plane parallel to the selection.

• The 3D axis origin is equal to the bounding sphere centre or to the bottom left corner of the view box containing the bounding sphere.

• The box overall dimensions are computed to hold the bounding sphere.

• The reference elements that can be selected for view creation are:

  Reference objects that can be selected
  Plane
  Sketch
  Face
  FTA view
  Inverse and Rotate of plane

• The direction of primary views created from 3D selection depends on the selection plane and the bounding sphere center. From the selection plane, the new primary view is created on the closest side from the selection. In this case you can see that the blue plane is created on the other side which is closer.

• If no selection is performed while creating a primary view, then the view type and its orientation on the view box is changed when the arrows of the blue knob are used.
  In this case you can see that as the arrows are clicked the view type and orientation is changing.