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This task shows how to apply an analysis on a sketch thru
different means such as by:
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In case you did not save the previous sketch, open the
Getting_Started.CATPart
document. |
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Using the Parents/Children Command
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Right-click the tangency constraint from the
specification tree and select Parents/Children.
The Parents and Children dialog box is displayed. The elements
to which the selected constraint is related are shown within the dialog
box.
If you wish to see more details on the parents (here the circles), just
double-click one of the element in the dialog box.
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Click OK in the dialog box.
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Using the Sketch Solving Status
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Select Circle.2.
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Click Constraints Defined in Dialog Box
in the Constraints toolbar.
The
Constraint Definition dialog box is displayed.
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Select the Radius / Diameter option.
The geometry
color has turned to purple meaning that it is over-constrained.
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Click OK in the dialog box.
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Click Sketch Solving Status
from the 2D Analysis Tools in the Tools toolbar.
This command gives you a quick diagnosis of the geometry status.
The Sketch Solving Status dialog box is displayed and informs
you of the general sketch status, whether it is under, over or iso-constrained.
Meanwhile, the information given in the Sketch Solving Status
dialog box is highlighted in red in the geometry area and the element
that are here under-constrained are highlighted.
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Using the Sketch Analysis
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The Sketch Solving Status dialog box is still
displayed. Click Sketch Analysis
available in the Sketch Solving Status dialog box.
The Sketch Analysis dialog box is displayed and information is
given on every element of the sketch as long as the created constraints
in the diagnostic tab.
Construction elements appear with a blue color in the geometry.
Note that you have the possibility to sort the elements displayed in the
dialog box by Name, status or Type, by clicking the appropriate tab. Note
that you can select elements from the dialog box and they will be
highlighted in the geometry area.
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Note that you
can now identify the construction elements and, for instance, swap them
into standard elements.
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Select Hide Construction Geometries
from the Sketch
Analysis dialog box.
All the construction elements are hidden both from the dialog box
and the geometry area. These elements are grayed in the specification
tree.
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Now select Hide Constraints
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All the constraints are hidden both from the geometry and the
dialog box. These elements are grayed in the specification tree.
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Note that the green color shows you that the whole geometry is now
constrained.
For more details on the Sketch analysis command, see
Analyzing Sketched Geometry. |