Product to Part

This task will show you how to filter a CATProduct into a CATPart, i.e. how to remove sensitive information from a CATProduct and create a new CATPart with the remaining geometry as follows:
Shown geometry
Graphic attributes
Axis system
always kept
Colors and attributes on instance and subelements optional

Any data other than the ones described above are removed in the newly created CATPart.
An option is also available to merge the bodies of each part into one body.
Note that the In Work Object in the result part is always the PartBody.

In this task, you will find:

If a memory error or a memory warning occurs, or if the input document is corrupted, the output part will be empty.
Open the 01_Cric_Assembly.CATProduct from the samples directory. It looks like this:

  1. Click Product to Part and select the node Assembly_01.

  2. The dialog box is displayed.

  3. Click OK. A progress bar is displayed while Assembly_01_AllCATPart is created.

    It looks like this:

Standard behavior

  • You can select any node in the CATProduct structure. Only this node and the elements it contains will be filtered, enabling you to create a CATPart with only a portion of your product.
  • A CATPart is created. Its default name is "Name_of_Node_of_Original_CATProduct"_AllCATPart and can be edited.
  • A body is created in the resulting CATPart for each body containing shown geometries under the node you have selected.
    Its name is the full path of the instance in the original CATProduct.
  • The geometries found are transferred as solids, surfaces or wireframes and placed in the corresponding bodies in the resulting CATPart.
  • The solids are created with the graphic properties (color, line type, line thickness, transparency) of their original body,
    the surfaces and wireframes are created with the graphic properties of their original feature.
  • All positions of the geometries are kept in the resulting CATPart.
    The origin of the resulting CATPart is created relatively to the higher root product currently open in V5
    (which is not necessarily the node you have selected).



You can select several options to transfer some elements that are not transferred in the standard behavior. For more information, see the Product to Part Options chapter.