-
Click New Machine .
-
Click Fixed Part
.
The New Fixed Part dialog box is displayed. |
|
-
Select the FixedPart_DU product from the specification
tree or from the geometry area.
The FixedPart_DU leaf appears in the specification tree under the
Mechanisms node. |
-
Click Prismatic Joint .
The Joint Creation Prismatic dialog box appears (the
image below shows the dialog box once it contains the correct
information). |
|
-
Enter YAxis in the Joint name
field.
-
Select the Y axis of YAxis_DU_1 for Line1,
and select Y axis of FixedPart_DU (AxisSystem.1) for
Line2.
-
Select the XY plane of YAxis_DU_1 for
Plane1, and select XY plane of FixedPart_DU (AxisSystem.1)
for Plane2.
-
Select the Length driven checkbox, and click
OK.
An Information message appears. |
|
-
Click OK.
-
Use the table below for information on creating two other
prismatic joints or revolute joint. In all cases, select the
Length driven checkbox or Angle driven checkbox.
Joint Name |
Joint Type |
Line1 |
Line2 |
Plane1 |
Plane2 |
Part 1 |
Part 2 |
ZAxis |
Prismatic |
Z axis |
Z axis |
ZX Plane |
ZX Plane |
ZAxis_DU_1 |
YAxis_DU_1 |
XAxis |
Prismatic |
X axis |
X axis |
XY Plane |
XY Plane |
XAxis_DU_1 |
FixedPart_DU (AxisSystem 2) |
CAxis |
Revolute |
Z axis |
Z axis |
XY Plane |
XY Plane |
CAxis_DU_1 |
XAxis_DU_1 |
-
Define the tool mount part and point as the ZAxis_DU_1.
-
Double-click on the Tool Mount Point
leaf on the specification tree.
-
Select the compass by the red square and move it to
the ZAxis_DU_1 part; position it as shown.
-
On the specification tree, click on the ZAxis_DU_1
part node.
The Set Location dialog box appears.
-
Click OK.
|
-
Define the workpiece mount part and point as the
CAxis_DU_1 part.
-
Double-click on the Workpiece Mount Point
leaf on the specification tree.
-
Select the compass by the red square and move it to
the CAxis_DU_1 part; position it as shown.
-
On the specification tree, click on the CAxis_DU_1
part node.
The Set Location dialog box appears.
-
Click OK.
|
-
Save the .CATProduct file for later use as a template.
Adding the Parts for Dressup
|
-
Right-click on the DressupMachine node at the top of the
specification tree, and select Components > Existing Components.
-
Navigate to the online/mtbug_C2/samples/V5/Mechanism_Dressup
directory.
-
Select the following parts:
- ZAxis.CATPart
- CTable.CATPart
- XAxis.CATPart
- YAxis.CATPart
- Base.CATPart
|
-
Select all of the _DU components and click Hide/Show .
-
Position the parts per the template parts.
-
Right-click on the compass, and select Snap
Automatically to Selected Object.
-
Select the Base part.
The compass snaps to the part when it is selected. |
-
Right-click on the compass, and select Edit.
The Parameters for Compass Manipulation dialog
box appears. |
-
Position and orient the parts so that the options
in the dialog box are those as shown below.
-
Select each of the other parts and position
according to the dialog boxes shown below.
YAxis part
|
|
ZAxis part
|
|
XAxis part
|
|
Ctable part
|
|
|
-
Click Mechanism Dressup .
The Mechanism Dressup dialog box appears. |
|
-
Click the New Dressup button.
|
|
This step indicates the mechanism on which the dressup is to be
defined. |
-
Click OK.
The Mechanism Dressup dialog box refreshes so that the
Available products list contains the products defined
above. The products need to be linked with the already defined
mechanism. |
|
-
In the Link list, select FixedPart_DU.1,
and from Available products, select Base.1.
-
Repeat for the remaining products using the table below.
Link |
Available product |
Z_Axis_DU_1.1 |
ZAxis.1 |
Y_Axis_DU_1.1 |
YAxis.1 |
X_Axis_DU_1.1 |
XAxis.1 |
C_Axis_DU_1.1 |
CTable.1 |
FixedPart_DU.1 |
Base.1 |
-
Click OK.