|This task shows you how to define macros on an
axial machining operation.
This is done using the Macros tab page of the machining operation editor.
For more general information about macros, see NC Macros.
The following macro types can be defined on axial machining operations:
Some specific axial machining operations support additional macro types:
|In addition, the following icons allow you to:
A sensitive icon representing the elementary paths of the macro will help you to build or edit your macro. The current macro path is colored violet. Right-clicking a macro path gives you access to a contextual menu.
If you create a machining operation and there are other operations of the same type in the program, it will inherit the macros used in the most-recently edited operation of the same type. An operation is considered edited when you click OK to quit the operation definition dialog box.
|Create a Drilling operation as described in the Prismatic Machining User's Guide.|
|1.||Double-click the Drilling operation in the specification tree to edit that operation.|
|2.||Select the Macros tab page in the operation definition dialog box. The initial status of all the macros in the Macro Management list is Inactive.|
|3.||Right-click the Approach macro line
and activate the macro by means of Activate.
In the Current Macro Toolbox, select Add Axial Motion . A sensitive icon representing the elementary paths of the macro appears.
|4.||Double-click the displayed value in order to edit it. A dialog box appears to allow you to specify the desired distance (30mm, for example).|
|5.||You can then click Replay to check the axial approach. The status of the macro becomes Up to date.|
|6.||Activate the Retract macro in the Macro Management list, and create a 30 mm axial retract motion in the same way.|
Activate the Linking Retract macro in the Macro Management list, and create a 25mm axial retract motion for the linking macro.
In the same way create a 25mm axial motion for the approach portion of the linking macro.
You can then click Replay to check the defined motions. The status of the macros change to Up to date.
Note that if a jump distance is defined on the operation, it will be used in preference to the linking macro. Similarly if local entry/exit distances are defined on the operation, they will be used in preference to the linking macro.
|8.||Click Replay to validate the tool path.
In the Replay dialog box, select the Different colors mode in order to visualize feedrate changes. The tool path is displayed with the following colors:
|9.||Click OK to accept the modifications made to the
The operation is updated with the specified macros.
PP Words in Macros
The PP Words Selection dialog box is displayed. You can enter the syntax in the following ways:
For Circular Milling operations, you should select the NC_CUTCOM_ON
instruction in the list of available syntaxes if you want the program to
interpret cutter compensation automatically (that is, by a CUTCOM/LEFT or
CUTCOM/RIGHT instruction). If you choose different syntax in the list, it
will be used as selected.