Creating a Welding Symbol

This task will show you how to create a welding symbol. You can set text properties either before or after you create the text.
Welding symbols
Square butt weld
Singe V butt weld
Single bevel butt weld
Flare V butt weld
Flare bevel butt weld 
Single U butt weld
Single J butt weld
Fillet weld
Spot weld
Back weld
Steep-flanked single-bevel butt weld
Steep-flanked single-V weld
Plug weld
Removable backing strip used
Permanent backing strip used
Surfacing weld
V flare weld
Spot weld
Complementary symbols
Weld with flat face
Weld with convex face
Weld with concave face
Flush finished weld
Fillet weld with smooth blended face
Finish symbols
C finish symbol
F finish symbol
G finish symbol
H finish symbol
M finish symbol
R finish symbol
Complementary indications
Field weld
Weld-all-around
Weld text side (up or down)
Indent line side (up or down)
Weld tail
Reference
Open the Brackets_views03.CATDrawing document.

  1. Click the Welding Symbol icon from the Annotations toolbar (Symbols sub-toolbar).

  2. Select an element or click in the free space to position the leader anchor point, and then click to validate. The welding leader will appear.

  3. Move the cursor to position the welding symbol and then click at the chosen location.

    The Welding creation dialog box is displayed.

  4. Type the desired values in the upper and/or lower field(s).

  5. Click the symbol buttons to choose the welding symbol, complementary symbols and/or finish symbols.

    The welding symbols available depend on your standard.

  6. If you want to add complementary indications like a field weld or a weld tail, for example, click the appropriate button.

  7. Click OK.

    The welding symbol is created.

  8. If needed, modify the welding symbol position by dragging it to the required location. 

  9. Double-click on the welding symbol to edit it,  and change the weld text side for example by clicking the Up/Down switch button.
  • If you have selected the Use style values to create new objects option in Tools > Options > Mechanical Design > Drafting > Administration tab, the Welding creation dialog box is pre-filled with custom style values (as defined in the Standards Editor). In this case, Properties toolbars and the Tools Palette are disabled during the creation of the welding symbol.
    On the other hand, if you have not selected this option, the Welding creation dialog box is pre-filled with the last entered values (if any). In this case, Properties toolbars and the Tools Palette are active during the creation of the welding symbol.
  • You can reset the current style values in the Welding creation dialog box at any time using the Reset button.
  • You can close the tail (reference) using a rectangle variable-size frame. For more information about adding frames, refer to Adding Frames or Sub-Frames. 
  • At any time, you can modify the welding symbol. To do this, double-click the welding symbol to be modified and enter the modifications in the displayed dialog box.
  • You can import a plain text file (.txt) to use as a reference (specification, process or other) by clicking the Import File button.