Assembly Add 

This task  shows you how to add several parts belonging to a same product.
Open the AssemblyRemove_Add.CATProduct document, perform the Asssembly Remove as explained in the documentation and put Part5 and Body.5 in show mode.
1.   Click the Add icon:
2.  Select Body.5 as the body to be added.

The dialog box that appears displays the names as well as the paths of the parts that may be affected by the add operation.
The assembly feature's name now appears in the top left corner of the dialog box. If desired, you can edit this name.

3.  The frame 'Affected parts' is exclusively reserved for the parts you wish to use. For the purposes of our scenario, you are going to add Body.5 to Part5.

Move Part5 to the list 'Affected parts". To do so, select Part5 and click the  button.

The other three buttons lets you move the names of the parts from one list to another too:

  moves all selected parts to the list 'Affected parts'
  moves all selected parts to the list 'Parts possibly affected'
  moves the selected part to the list 'Parts possibly affected'
The Add dialog box that has appeared, indicates the part to be added.
4.  Check the option Highlight Impacted Parts to clearly identify the parts affected by the operation.

5. Click OK to confirm.
6.  To better visualize the result, put Part2 and Part3 in no show mode. You can see the portion of material that has been removed.

A new entity 'Assembly Features' appears in the specification tree. It contains the assembly removal referred to as 'Assembly Add.1" and the name of affected parts.

Moreover, this feature has generated a remove feature in Part5. An arrow symbol identifies this addition in the tree, meaning that a link exists between Assembly Add.1and this remove feature.


Editing an Assembly Add

  To edit an assembly add operation, double-click 'Assembly Add.X' entity. You can then modify the list of the parts possibly affected by the addition.

Reusing Part Design Add Features

  To increase your productivity, you can create Assembly Add Features from existing Part Design Add features, or more precisely by reusing the specifications you entered for designing Part Design Add features. To do so, just proceed as follows:
  1.   Click the Add icon .
  2.  Select the Part Design add feature of interest.
  3.  Both the Add Definition and the Assembly Features Definition dialog boxes display. You then just need to specify the parts of interest. 

The assembly add feature inherits the specifications as displayed in the Part Design add Definition dialog box. You can edit these specifications at any time. Editing an Assembly feature created in this way does not affect the specifications used for the Part Design feature.


Reusing Assembly Design Add Features

  The application also lets you reuse Assembly Add Features' specifications to accelerate the design process. In this case, you just need to select the existing assembly add feature, click the Assembly add icon and then select a face. Only the Assembly Features Definition dialog box appears to let you determine the parts of interest.