Enter 22 as the pocket depth value.
Selecting a second limit is mandatory. Select Pad1
top face as the second limit.
Your specifications for creating the pocket are now defined.
Let's go on with the draft
definition. Enter 7 as the draft angle value.
Drafting faces is optional. If you do not wish to use this capability,
just uncheck the Angle option.
Check the Second limit option to define the
neutral element. So, note that the pad top face is also used as the
Enter 4 as the radius value to define the three
Lateral radius: defines the fillets on vertical
First limit radius: defines the round corner
Second limit radius: defines the filets on the
edges of the second limit.
Filleting edges is optional too. If you do
not wish to use this capability, just uncheck the options.
Click Preview to check if the
application can compute the fillets properly.
Clicking Preview previews the pocket, the draft and the
fillets and display them in the specification tree. If you have
deactivated the draft or fillet options, the draft or the fillets are
then displayed as deactivated features in the tree, i.e. with red
In the specification tree red parentheses appear on EdgeFillet.1,
meaning that it cannot be computed by the application. Looking more
closely at this fillet you can see that due to the shape of the initial
sketch, it is effectively impossible to compute that fillet.
Note that there is a priority in the order of appearance
of the fillets (from top to bottom) in the specification tree. The first
fillet corresponds to the Lateral radius option in the dialog
box, the second fillet to the First limit radius option and
the last fillet to the Second limit radius option.
Click OK to create the features.
If you look at the specification tree, you will note that you have
- one pocket
- one draft
- two fillets
This implies that if you want to edit the drafted
filleted pocket, you need to double-click the appropriate feature. This
is your new part: