Create a Multi-Axis Curve Machining Operation

task target This task shows you how to insert a Multi-Axis Curve Machining operation in the program.
scenario

  1. Select the Multi-Axis Curve Machining icon .
    The Multi-Axis Curve Machining dialog box appears directly at the Geometry page .

  2. Set the curve machining mode to Between 2 Curves and in the sensitive icon set the curve machining type to Side. 

  3. Select the red top guiding curve in the sensitive icon then select the desired guiding curve in the part.

  4. Select the two limit points of the curve.

  5. Double click the Axial Offset 1 parameter in the sensitive icon,
    then enter a value of -5mm in the Edit Parameter dialog box. 

  6. Select the Strategy tab page and set the Tool Axis direction to (0, -1, 0).
    Choose Interpolation as the Tool axis mode.

  7. Click one of the red tool axes in the sensitive icon,
    then specify the orientation of the interpolation axis at the start of machining.
    You can do this by selecting a surface. In this case the surface normal is used.

  8. Click the other red tool axis in the sensitive icon,
    then specify the orientation of the interpolation axis at the end of machining.

  9. The tool axis will be interpolated between these two axes. 

  10. Click Tool Path Replay to replay the operation as described previously. 

  11. Click OK to exit the replay mode and return to the Multi-Axis Curve Machining dialog box.

  12. Click OK to create the operation in the program. 

end of task