Right-click Body.1 and select the Copy
The PartBody contains the geometry of Solid Functional Set.1.
Open a new CATPart document and position the cursor
anywhere in the specification tree.
Select Edit -> Paste Special....
The Paste Special dialog box that appears proposes
three paste options:
As specified in Part document:
the object is copied as well as its design specifications.
As Result With Link: the object is copied without
its design specifications and the link is maintained between the
reference and the copy.
As Result: the object is copied without its design
specifications and there is no link between the reference and the
For our scenario, select the As Result With Link
option if not already selected.
Click OK to confirm.
Solid Functional Set.1 is copied into the new document. You will
notice that the specification tree displays it under the name of
Solid.1. A cube
represents this solid.
Return into the first document to edit the original
geometry. For example, enlarge Sketch.1 which supports the
Then, use the Part Design Edge Fillet
command to fillet the lateral edge as shown:
Take a look at the new document: the cube
graphic symbol used for Solid.1 in the tree now contains a red cross.
This means that the initial PartBody underwent transformations.
To integrate the changes, you need to use the
Synchronize contextual command. To do so, right-click Solid.1
object and apply the command.
You can observe that the copy reflects the change: the
shellable feature is enlarged and the new edge fillet is added.