Variable Radius Fillet

The Variable Radius Fillet command creates a curved face of a variable radius that is tangent to, and that joins two surfaces. A variable radius corner means that at least two different constant radii are applied to two entire edges.

The command allows you to define the two types of variation to the variable radius fillet:

  • Cubic
  • Linear
Open the Variable_Fillet.CATPart document.

  1. Click the Variable Radius Fillet icon .
    The Variable Radius Fillet Definition dialog box is displayed. Default options let you define a Cubic variation of the Variable Fillet.

  2. Select the edge to be filleted. You can define variable radius fillets on closed edges.
    The application detects both vertices and displays two identical radius values.

  3. Double-click on the radius to access the Parameter Definition dialog box. For example, enter 50mm.

  4. Click the icon at the right of the Points field. Select Variable_Plane in the geometry.

  5. Double-click Variable_Plane radius. For example, enter 10mm.


     

  6. Select OK in Variable Radius Fillet Definition dialog box.


     
You can select the Conic parameter check box. This check box allows you to vary the section of the fillet.
For a parameter comprised between or equal to:
  • 0.5, the resulting curve is a parabola.
  • 0 < parameter < 0.5, the resulting curve is an arc of an ellipse.
  • 0.5 < parameter < 1, the resulting curve is a hyperbola.
  • Conical fillets do not handle twist configurations. If a twist is detected, the fillet
    operation fails.
  • Conical fillets may produce internal sharp edges due to a curvature discontinuity of the
    fillet supports. Healing is used to smooth these sharp edges.
  • If the fillet surface curvature is lower than the support curvature, fillet surface
    relimitation may fail. In such cases, the conic parameter has to be decreased.

Limiting Elements

  • To edit this fillet, double-click EdgeFillet.1 in the specification tree. Click the More button to access the Limiting element option.

    		•

    		Four additional options are available. To know how to use:

    1. Click the icon of Limiting element(s) field, then select Limit_Plane in the geometry.

    2. Click this arrow to reverse the direction and therefore specify the portion of material that will be kept.

    3. Click OK.
      The variable radius fillet is trimmed to Limit_Plane. The final part looks like this: