Introducing the Tolerancing Advisor 

This task introduces the Tolerancing Advisor.
The Tolerancing Advisor lets you create allowed annotations according to the selected geometrical element or existing annotation.
  Allowed annotations are:
  • Semantic (Dimensions) and non semantic annotations (Text, Roughness, Flagnote). See Semantic Control settings.
  • Datum.
  • Datum target.
  • Datum reference frame.
  • Semantic and non semantic annotations can be created on constant sections of variable fillets.
  • Related Geometric feature type:
    • Angular Dimension Related to an Origin and Linear Dimension Related to an Origin are now available.
    • A revolute circle can be seen as a plane with its revolute axis seen as its normal.
    • The InvertOriented button in the Limit of Size Definition dialog box enables you to invert the orientation of a Related Dimension.
    • The options Symmetric Lower Limit and Single limit in the Limit of Size Definition dialog box may not be active nor modifiable according to the elements selected.
    • If the option Always try to create semantic tolerances and dimensions is active, it takes the above into account.
  Remember that:
  • When the dimension supports are related to a parameter (sketch's constraints, knowledge, etc) for which tolerances are still defined, they are taken into account for the dimension tolerances.
Open the Tolerancing_Annotations_01.CATPart document:
 

  1. Click Tolerancing Advisor in the Annotations toolbar.

  2. The Semantic Tolerancing Advisor dialog box appears.

    This is the minimal appearance for this dialog box because no geometrical element or annotation has been selected and no datum reference frame has been created yet.

  3. Select the surface as shown on the part.

  4. The Semantic Tolerancing Advisor dialog box is updated according to the selected surface.

    • The Commands frame contains all the semantic annotations that will be created in relation with the selected element and the geometrical feature type.
    • The Commands frame contains a combo list for all capabilities applying for the selection.
    The Propagation Selection options are displayed according to the type of face selected depending on the canonicity. In this scenario the options are not used. For more information, refer to Propagating Geometry Selection for Feature Creation.

  5. Click Text with Leader (One surface):

  6. Enter Milling in the Text Editor dialog box when it appears.

  7. Click OK in the dialog box.

    The annotation text  is created.
    The Semantic Tolerancing Advisor dialog box is updated.
    The Text with Leader icon is orange-colored:
    This color inform you that an annotation has been created; you can still create other annotations.

  8. Click Close in Semantic Tolerancing Advisor dialog box.