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This task shows how to create a circle. In this task, we will use the
Sketch tools toolbar but, of course you can create this circle
manually. For this, move the cursor to activate SmartPick and click as soon
as you get what you wish. |
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By default, circle centers appear on the sketch. In case you create
circles by clicking, if you do not need them, you can specify this. |
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Click Circle
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The Sketch tools toolbar displays values for defining the
circle.
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Type in the Sketcher tools toolbar for the
circle center: H=30mm, V=30mm and press Enter.
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Type in the Sketcher tools toolbar for the
point on circle: R=20mm and press Enter.
The circle is created. |
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Constraints are similarly assigned to this
circle on the condition you previously activated the Dimensional
Constraints option
in the Sketch tools toolbar. |
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Double-click to edit the offset constraint corresponding
to the radius.
The Constraint Definition dialog box appears.
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Select Diameter in the Dimension
combo list and click OK.
The offset constraint type has been changed to diameter.
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Copying the Circle Radius Parameters
Once you have created one circle, you can create
any other and in the meantime use the radius parameter from the circle
first created. To do this:
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Click Circle
.
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Right-click the first circle and select Parameter
> Copy Radius from the contextual menu.
The new circle is automatically created with the radius of the circle
first created but not positioned.
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Click to indicate the second circle location or use the
Sketch tools toolbars to specify the circle center.
The new circle is positioned.
Changing the Circle Radius
Once you have created a circle, you can change
its radius. To do this, you can:
Otherwise:
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If the circle center is fixed (or
iso-constrained), you can change the circle radius by using one of the
methods explained above. |