Use Case: Creating an Engine Head and its Mold

The scenario described below aims at illustrating the use of  CATIA Instant Collaborative Design. This scenario shows the development of a part by a designer and the creation of a mold based on this part by another designer.
Two different designers take part in this scenario:
This symbol is used throughout the scenario to symbolize the part designer.
This symbol is used throughout the scenario to symbolize the mold designer.

  1. Open the Enginehead.CATPart file.

  2. From the Tools->Options menu, access the Infrastructure->Collaboration Infrastructure category.

  3. In the Network tab, check the Client/Server Mode to specify the selected communication mode and enter the connection settings in the Connectivity tab.

  4. In the Collaboration Server Connect dialog box, enter your name, password and role. Click OK when done.

  5. Click the Workspaces icon ().

  6. Click the New button in the Workspaces dialog box to create a new workspace. Fill in the fields (see below).

  7. Select the workspace you have just created and click the Join button to join it. The workspace status turns to Active. Click Close when done.

  1. From the Tools->Options menu, access the Infrastructure->Collaboration Infrastructure category.

  2. In the Network tab, check the Client/Server Mode to specify the selected communication mode and enter the connection settings in the Connectivity tab.

  3. In the Collaboration Server Connect dialog box, enter your name, password and role. Click OK when done.

  4. Click the Workspaces icon ().

  5. Select the Engine Head workspace and click the Join button. Click Close when done.

  1. From the Start->Mechanical Design menu, access the Functional Molded Part workbench.

  2. In the specification tree, right-click the Base Profile located below the Sketches node and select the Hide/Show command. The following sketch displays:

  3. Click the Shellable Feature icon () and click the Base Profile sketch. The Shellable Feature dialog box displays:

    • Click the Draft tab and select the Intrinsic to feature option in the Draft behavior scrolling list.

    • Click OK when done.

  4. In the specification tree, right-click the Mold Block Profile located below the Sketches node and select the Hide/Show command. The following image displays:

  5. Select the Mold Block Profile and click the Share Selected Entities icon () in the Instant Collaboration toolbar. The Briefcase window opens.

    • Enter the subject of the briefcase: Mold Block Sketch.

    • Check Show all check box to see all the entities.

    • Click OK when done. The briefcase is sent to the cast designer.
 

  1. In the specification tree, right-click the Top Cut Surface located bottom of the Sketches node and select the Hide/Show command. The surface displays.

  2. Click the Cut icon (): The Cut window displays.

    • Select the main body in the geometry: Shellable Prism.1 displays in the Features to cut field.

    • Select the Top Cut Surface: Top Cut Surface displays in the Cutting element field.

    • Click the Arrow located on the Top Cut Surface to reverse the direction.

    • Check the Fillet Radius check box, set the radius to 8mm, and click OK when done.

     

  3. Right-click the Top Cut Surface in the geometry and select the Hide/Show command to hide it.

  4. Right-click the Mold Block Profile and select the Hide/Show command to hide it.

  5. Click the Main Body from the specification tree and click the Share Selected Entities icon () in the Instant Collaboration toolbar. The Briefcase window opens. Enter the subject of the briefcase: Main body and click OK. The briefcase is sent.

  1. From the Start->Mechanical Design menu, access the Functional Molded Part workbench and create a New Part.

  2. Click the Briefcases open/close icon () to list the existing briefcases. The ones you received display in the To Merge tab.

  1. Click the Mold Block Sketch and click the Merge button. After you merged it, you would notice the entity you just merged disappeared and moved in Merged tab. 

  2. Select the Main Body and click Open button. Briefcase window appears. Check Show all check box to see which entities you are receiving.

  1. Click the Merge button.

  2. Select Body.1 in the specification tree and rename it to Mold Block.

  3. In the External Volume toolbar, click the Added Feature icon (). The Added Feature dialog box displays:

    • Select the Mold Block Profile in the geometry.

    • Set the First Length to 50 mm.

    • Set the Second Length to 10 mm. Click OK when done.

  4. Right-click the Mold Block and select the Hide/Show command.

  1. Double-click the Shell Properties.1 located below the Functional Body.1 in the specification tree. The Shell Properties dialog box displays.

    • Select the Functional body: Cut.1\Face.1 displays in the Faces to remove field.

    • Change the thickness to 1.2mm.

    • In the Advanced tab, change the thickness to 4mm, select Face.1 of Main Body for Faces, and click OK when done.

  2. Click the Shell Properties in the geometry and click the Share Selected Entities icon () in the Instant Collaboration toolbar. The Briefcase window opens. Enter the subject of the briefcase: Shell Properties. Check Show all parents checkbox to see what other entities will be sent along with Shell Properties. Click OK. The briefcase is sent.

 

  1. In the specification tree, right-click the Bottom Pocket Sketch located below the Sketches node and select the Hide/Show command.

  2. Click the Pocket icon () and select the Bottom Pocket Sketch in the geometry. The Pocket window displays.

    • Set the Floor length to 10mm in the Distance tab.

    • In the Fillet tab, check the Floor radius check box, and set the radius to 2mm.

    • Check the Protected volume check box.

    • In the Wall Type scrolling list, select the Enter thickness option.

    • Set the Thickness to 2mm.

    • In the Draft tab, select Intrinsic to feature in the Draft behavior scrolling list. Click OK when done.

  3. Click the Pocket in the geometry and click the Share Selected Entities icon () in the Instant Collaboration toolbar. The Briefcase window opens. Enter the subject of the briefcase: Pocket and click OK. The briefcase is sent.

  1. Click the Briefcases open/close icon () to list the existing briefcases. The ones you received display in the To Merge tab.

  2. Select Shell Properties briefcase and click the Merge button.

  3. Select Pocket briefcase and click the Merge button.

  4. From the Start->Shape menu, access the Generative Shape Design workbench.

  5. Zoom in to enlarge your part.

  6. Right-click the Sketches node and select the Define In Work Object command.

  7. Select the Functional Solid.1\Face (see graphic below) and click the Offset icon
    (). The Offset Surface Definition window displays. Click OK to close the dialog box.

  8. Select the Functional Solid.1\Face\Main Body and click the Offset icon (). The Offset Surface Definition window displays. Click OK to close the dialog box.

  1. Select the other Functional Solid.1\Face\Main Body and click the Offset icon (). The Offset Surface Definition window displays. Click OK to close the dialog box.

  2. Click the Join icon (). The Join Definition dialog box displays.

    • From the specification tree, select Offset.1, Offset.2, and Offset.3.

    • Click OK when done.

  3. In the specification tree, right-click the Mold Block Profile (below the Geometrical Set.2 node) and select the Hide/Show command. The profile displays.

  4. Click the Mold Block Profile in the geometry and click the Fill icon ( ). The Fill Surface Definition dialog box displays. Click OK when done.

  5. Right-click the Main Body in the specification tree and select the Hide\Show command.

  6. Zoom out, right-click the Mold Block Profile and select the Hide\Show command.

  7. Click the Trim icon (). The Trim Definition dialog box displays:

    • Select Join.1 from the specification tree.

    • Select Fill.1 from the specification tree.

    • Click OK when done.

  8. From the Start->Mechanical Design menu, access the Functional Molded Part workbench.

  9. Right-click the Mold Block body in the specification tree and select the Hide/Show command. The body displays.

  10. Right-click the Mold Block body in the specification tree and select the Define in Work Object command.

  11. Click the Divide icon (), the Divide dialog box displays:

    • Mold Body will be selected in the Body to divide field.

    • Select Trim.1 from the specification tree for Divide element.

    • Click OK when done.

  12. After the Divide, Divide Body.2 and Divide Body.3 were created. Rename them to Upper Mold Block and Lower Mold Block.

  13. Right-click the Mold Block in the specification tree and select the Hide/Show command to hide.

  14. Right-click the Lower Mold Block in the specification tree and select the Hide/Show command to hide.

  15. Right-click the Upper Mold Block in the specification tree and select the Hide/Show command to hide. And right-click the Lower Mold Block in the specification tree and select the Hide/Show command to display.

  16. Right-click the Lower Mold Block in the specification tree, and select the Hide/Show command.

  17. Select the Main Body and select the Hide/Show command. The Main Body displays.

  1. In the specification tree, right-click the Middle Ribs Sketch located below the Sketches node and select the Hide/Show command. The Ribs sketch displays.

  2. Click the Rib () icon and select the Ribs in the geometry. The Rib dialog box displays:

    • In the Distance tab, set the First limit to To shell.

    • Click the Reverse direction button.

    • In the Wall Type scrolling list, select the Enter thickness option and set the thickness to 3mm.

    • In the Draft tab, set the Draft behavior to Intrinsic to feature.

    • Click OK when done.

  1. In the specification tree, right-click the Outer Ribs Sketch located below the Sketches node and select the Hide/Show command. The Outer Ribs sketch displays.

  2. Click the Rib () icon and select the outer ribs in the geometry. The Rib dialog box displays:

    • In the Distance tab, set the First limit to To Shell.

    • Click the Reverse direction button.

    • In the Wall Type scrolling list, select the Enter thickness option and set the thickness to 20mm.

    • In the Draft tab, set the Draft behavior to Intrinsic to feature.

    • Click OK when done.

  3. Click the Share Selected Entities icon () in the Instant Collaboration toolbar and select Rib.1 and Rib.2 in the specification tree. The Briefcase window opens. Enter the subject of the briefcase: Ribs and click OK. The briefcase is sent.

  1. In the specification tree, right-click the Center Hole Sketch located below the Sketches node and select the Hide/Show command. The Center Hole sketch displays.

  2. Click the Cutout () icon: the Cutout window displays. Select the Center Hole Sketch in the geometry.

    • In the Distance tab, set the Floor to Through All.

    • Set the Wall Type to Enter thickness and set the thickness to 0.

    • Click OK when done.

  3. Click the Cutout you have just created in the specification tree and click the Share Selected Entities icon () in the Instant Collaboration toolbar. The Briefcase window opens. Enter the subject of the briefcase: Center Hole and click OK. The briefcase is sent.
 

  1. In the specification tree, right-click the Side Cutout Sketch and the Center Cutout Sketch located below the Sketches node and select the Hide/Show command. The sketches display.

  2. Click the Cutout () icon: the Cutout window displays. Select the Center Cutout Sketch in the geometry.

    • In the Distance tab, set the Floor length to 28mm.

    • Click the Reverse Direction button.

    • In the Draft tab, set the Draft behavior to Intrinsic to feature.

    • Click OK when done.

  3. Click the Cutout () icon: the Cutout window displays. Select the Side Cutout Sketch in the geometry.

    • In the Distance tab, set the Floor length to 36mm.

    • Click the Reverse Direction button.

    • In the Draft tab, set the Draft behavior to Intrinsic to feature.

    • Click OK when done.

  4. Click the two Cutouts you have just created in the specification tree and click the Share Selected Entities icon () in the Instant Collaboration toolbar. The Briefcase window opens. Enter the subject of the briefcase: Center-Side Cutouts and click OK. The briefcase is sent.

  5. In the specification tree, right-click the Bolt Hole Sketch located below the Sketches node and select the Hide/Show command. The Bolt Hole Sketch displays.

  6. Click the Cutout () icon: the Cutout window displays. Select the Bolt Hole Sketch in the geometry.

    • In the Distance tab, set the Floor to Through All.

    • Click OK when done.

  7. Click the Cutout you have just created (CutOut.4) in the specification tree and click the Share Selected Entities icon () in the Instant Collaboration toolbar. The Briefcase window opens. Enter the subject of the briefcase: Bolt Holes and click OK. The briefcase is sent. You are done with the design. Click here to display the result sample part.

  1. Click the Briefcases open/close icon () to list the existing briefcases. The ones you received display in the To Merge tab.

  2. Click the Ribs briefcase and click the Merge button.

  3. Click the Center Hole briefcase and click the Merge button.

  4. Click the Center-Side Cutouts briefcase and click the Merge button.

  5. Click the Bolt Hole briefcase and click the Merge button.

  6. Expand the Functional Body.1 node and right-click Cutout.4 feature, select the Cutout.4 object-> Deactivate command.

  7. Right-click Cutout.1 feature, select the Cutout.1 object-> Deactivate command.

  8. Select the Lower Mold Block in the specification tree, and select the Hide/Show command to display.

  9. Click the Fitting icon (), the Fitting dialog box displays:

    • Click the Main Body. Main Body displays in the Tool body field.

    • Set Clearance to 1mm and click OK when done.

  10. Right-click the Upper Mold Block and select the Define in Work Object command.

  11. Right-click the Lower Mold Block and select the Hide/Show command.

  12. Right-click the Main Body and select the Hide/Show command.

  13. Click the Fitting icon (), the Fitting dialog box displays:

    • Click the Main Body. Main Body displays in the Tool body field.

    • Leave Clearance and click OK when done.

  14. Right-click the Upper Mold Block and select the Hide/Show command (see graphic below). Hide it again.

  15. Right-click the Lower Mold Block and select the Hide/Show command. The Lower Mold block displays. Click here to display the result sample file.